Skip to content
Back to Cutting parameters calculator

6061-T6 aluminum speeds and feeds

6061 aluminum in the T6 condition is turned at 400-1,000 m/min (about 1,310-3,280 SFM) with 0.25 mm/rev, milled at 250-600 m/min with 0.15 mm/tooth, drilled at 280-750 m/min and threaded at 140-450 m/min. It is the most widely machined aluminum alloy in the world and cuts practically the same as 6082, its European counterpart: spindle rpm and chip evacuation set the limit, not the material.

Designation
EN AW-6061 T6 · AlMg1SiCu
Hardness
95 HB
ISO group
Non-ferrous (N)
Turning Vc
400–1000 m/min

Which operation are you machining?

Recommended speeds and feeds

Turning

400–1000 m/min

0.25 mm/rev

400-1,000 m/min at 0.25 mm/rev with a polished, positive aluminum (ISO N) insert. The chip tends to come out long and spiral: use an aluminum chipbreaker or a slightly higher feed so it breaks. On small diameters, the spindle hits its rpm limit long before the insert reaches its cutting speed.

Milling

250–600 m/min

0.15 mm/tooth

250-600 m/min at 0.15 mm/tooth with polished 2 or 3-flute end mills with plenty of chip room. In deep pockets evacuation rules: air or high-pressure coolant so the cutter does not recut chips.

Drilling

280–750 m/min

0.25 mm/rev

280-750 m/min and 0.25 mm/rev with a carbide drill for aluminum. In deep holes chips pack in the flutes: peck every 3-4 diameters or use a through-coolant drill.

Threading

140–450 m/min

0.25 mm/rev

140-450 m/min for single-point threading. For tapping, use an aluminum tap with wide flutes and lubricant; in 6061-T6 a roll-form tap gives stronger threads and makes no chips.

Starting values for coated carbide in medium cutting. Fine-tune them in the calculator for your tool, type of pass and safety margin.

How it behaves when cutting

6061 is an aluminum alloy with magnesium, silicon and a little copper, around 95 HB in the T6 condition. It is soft, conducts heat very well and takes very high speeds without the edge suffering from temperature. Its problem, as with every aluminum, is that it sticks to the tool: if the edge is not sharp or the speed is too low, built-up edge forms and the surface comes out scratched. Annealed (O) or T4 material is even gummier; T6 machines best.

Keys to machining it in the shop

6061 vs 6082: almost the same material

6061 is the reference alloy in America and Asia, and 6082 its European equivalent. 6082 has slightly higher strength and 6061 a little copper that slightly improves anodized appearance, but on the machine they behave almost the same: same speeds, same feeds and the same chip problems. If an American drawing calls for 6061 and your stock is 6082, the program can stay the same; what needs confirming with the customer is whether the material substitution is acceptable for the part.

T6 and T651: why stress relief matters

T6 is the solution-treated and aged condition, the usual one for machining. Thick plate is normally ordered as T651, which is also stretched at the mill to relieve internal stress. The difference shows when you remove a lot of material: a non-stretched T6 plate can bow as stresses release, while T651 stays much flatter. On large parts with pockets, rough both sides, unclamp the part so it can relax and finish with light stock.

Finish, anodizing and burrs

6061 anodizes well, but anodizing reveals every tool mark, scratch or built-up-edge area. For parts going to anodize, use polished finishing cutters, avoid tool dwell on the surface and deburr before treatment. Remember too that anodizing adds a few microns of coating: on tight fits or threads, agree the allowance with whoever does the treatment.

Quick shop tips

  • Polished, positive tooling: a dull edge is what makes aluminum stick to the insert.
  • If the machine cannot reach the cutting speed, that is fine: raise the feed rather than push the spindle.
  • Order thick plate as T651 so the part does not bow as you pocket it.
  • Clear chips with air or high-pressure coolant: recutting them scratches the part.
  • For anodized parts, protect the finish: anodizing shows every defect.

Frequently asked questions

Are 6061 and 6082 aluminum the same?

They are not the same alloy, but they are very similar and machine the same way. 6082 is slightly stronger and is the European standard; 6061 is the standard in America and Asia.

What does T6 mean on 6061 aluminum?

That it has been solution treated and artificially aged to reach full strength. It is the normal condition for machining. T651 is the same with a stretch afterwards that reduces internal stress.

What rpm should I use to mill 6061?

It depends on the diameter: a 10 mm (3/8 in) end mill at 400 m/min (1,310 SFM) needs about 12,700 rpm. If your spindle cannot reach it, run at its maximum and set the chip load; in aluminum, running below the speed range does not harm the tool as long as the chip has enough thickness.

Can 6061 be machined dry?

Light milling, yes, with air blast or minimum quantity lubrication, as long as chips clear well. For deep holes, tapping and large pockets, coolant helps stop chips sticking and packing the tool.

Why does aluminum stick to my end mill?

A dull edge, a coating not suited to aluminum, too low a speed or chips that do not clear. Use polished uncoated or DLC/ZrN-coated end mills, raise the speed and clear the chips.

Similar materials

Related apps