Skip to content
Back to Cutting parameters calculator

Delrin / acetal (POM) speeds and feeds

Acetal (POM, best known by the Delrin brand) is turned at 250-500 m/min (about 820-1,640 SFM) with 0.2 mm/rev, milled in the same range at 0.15 mm/tooth, drilled at 80-200 m/min with 0.15 mm/rev and threaded at 60-150 m/min. It is the most machined engineering plastic: stiff, stable and with very low moisture absorption. Speed is not the issue; what matters is a very sharp tool and keeping heat from melting the material.

Designation
POM-C · Delrin = POM-H
Hardness
≈ 80 Shore D
ISO group
Non-ferrous (N)
Turning Vc
250–500 m/min

Which operation are you machining?

Recommended speeds and feeds

Turning

250–500 m/min

0.2 mm/rev

250-500 m/min at 0.2 mm/rev with a sharp, polished insert like those for aluminum. The chip comes out continuous and long: plan how to clear it so it does not wrap around the part. For finishing, low feed and a small nose radius so you do not push the material.

Milling

250–500 m/min

0.15 mm/tooth

250-500 m/min at 0.15 mm/tooth with polished 1 to 3-flute end mills with plenty of chip room. Aluminum end mills work well. Clamp lightly, because POM deforms under the vise and springs back when released.

Drilling

80–200 m/min

0.15 mm/rev

80-200 m/min and 0.15 mm/rev with a sharp drill. Heat is the problem in holes: peck to clear the chip and cool with air or coolant. If the drill loads up, the hole comes out tapered and undersize.

Threading

60–150 m/min

0.15 mm/rev

60-150 m/min for single-point threading with a sharp insert. For tapping, use a sharp cutting tap; plastic threads come out slightly small because the material springs back, so on critical fits try a sample part first.

Starting values for coated carbide in medium cutting. Fine-tune them in the calculator for your tool, type of pass and safety margin.

How it behaves when cutting

POM cuts cleanly and leaves an excellent finish, but it has two quirks. First, it conducts heat very poorly: if the tool rubs or the chip does not clear, heat stays in the cutting zone and the material softens, melts and leaves burrs. Second, it expands about ten times more than steel: a part measured hot straight off the machine can be out of tolerance once it cools. With a keen edge, positive rake and a chip that carries the heat away, it is very easy to machine.

Keys to machining it in the shop

Sharp tools and heat out of the cut

In POM a dull tool does not cut: it pushes, heats and melts the material. Use polished uncoated carbide or well-sharpened HSS with positive rake. Coatings designed for steel, with a slightly honed edge, do not help. The usual coolant is compressed air, which also clears the chip; soluble coolant works too, but clean the part thoroughly if it goes into food or medical use.

Expansion and tolerances: measure cold

POM expands around 0.1 mm per metre per degree, about ten times more than steel. On a 100 mm part, a 10 °C difference between the freshly machined part and the inspection room changes the size by about 0.1 mm (0.004 in). For tight fits: let the part cool before the final finishing pass, measure at room temperature and do not over-clamp in the vise. On parts with a lot of material removed, rough, rest and finish for more stable parts.

POM-C vs POM-H (Delrin): which is which

Delrin is the brand of POM homopolymer (POM-H): slightly stiffer and stronger, but more prone to centreline porosity in thick rod. POM-C (copolymer) is slightly less stiff, more dimensionally stable and has less centre porosity, which is why it is the most common grade in rod and plate for machining. They machine with the same parameters. If the part comes from the centre of a thick POM-H rod, check the functional area for voids.

Quick shop tips

  • Very sharp, polished tooling: a dull edge melts POM instead of cutting it.
  • Use compressed air to cool and clear chips; never let the tool rub.
  • Measure at room temperature: POM expands about ten times more than steel.
  • Clamp lightly: plastic deforms and springs back when released.
  • Overheated POM gives off formaldehyde: avoid burning it and ventilate the area.

Frequently asked questions

Are POM, acetal and Delrin the same?

Delrin is a trade name for POM homopolymer (POM-H), and acetal is the common name for POM. In the shop 'Delrin' often means any acetal, although copolymer (POM-C) is the most common in rod. They machine the same.

What tooling should I use for Delrin?

Polished uncoated carbide or well-sharpened HSS with positive rake. End mills and inserts for aluminum work very well in acetal.

Why does Delrin melt when drilling?

Because the heat cannot escape: a dull drill, too low a feed or chips packed in the flutes. Sharpen the drill, raise the feed, peck and cool with air.

Do I need coolant to machine acetal?

Not always. Compressed air is usually enough and avoids contaminating the part. For deep holes or long runs, soluble coolant helps control temperature and size.

What tolerances can you hold in Delrin?

With good technique, about ±0.05 mm (±0.002 in) on small parts without trouble. Tighter tolerances require controlling part temperature at inspection, resting between roughing and finishing and clamping without distortion.

Similar materials

Related apps