Skip to content
Back to Cutting parameters calculator

P20 / 40CrMnMo7 mould steel speeds and feeds

P20 mould steel (40CrMnMo7, 1.2311) is turned at 140-220 m/min (about 460-720 SFM) with 0.22 mm/rev using coated carbide, milled in the same range at 0.08 mm/tooth and drilled at 98-165 m/min with 0.14 mm/rev. It is the most common plastic injection mould steel and is supplied pre-hardened to around 300 HB (28-34 HRC), so it is machined at its final hardness with no heat treatment afterwards.

Designation
EN 40CrMnMo7 / 1.2311 · AISI P20
Hardness
300 HB
ISO group
Steel (P)
Turning Vc
140–220 m/min

Which operation are you machining?

Recommended speeds and feeds

Turning

140–220 m/min

0.22 mm/rev

140-220 m/min at 0.22 mm/rev for roughing with a coated steel (ISO P) grade; for finishing round cores and inserts, drop the feed to 0.1-0.15 mm/rev and use a 0.4-0.8 mm nose radius. If the block is above 32 HRC, stay at the low end of the range.

Milling

140–220 m/min

0.08 mm/tooth

Same 140-220 m/min range at 0.08 mm/tooth. To clear cavities, high-feed roughing (shallow depth, high feed) outperforms conventional roughing, always climb milling. With carbide end mills, air blast or dry cutting is better than flood coolant: sudden temperature changes crack the edge in a pre-hardened steel.

Drilling

98–165 m/min

0.14 mm/rev

98-165 m/min and 0.14 mm/rev with a through-coolant carbide drill. Mould cooling channels are long holes: beyond five diameters, reduce speed by 20% and program pecks, or use a gun drill for very deep holes.

Threading

49–99 m/min

0.14 mm/rev

49-99 m/min is the range for carbide threading (on the lathe or with a thread mill), which is the safest option in this steel. With HSS-E taps the speed is much lower, around 10-15 m/min, and a 65-70% thread engagement drill keeps you from breaking a tap in an expensive block.

Starting values for coated carbide in medium cutting. Fine-tune them in the calculator for your tool, type of pass and safety margin.

How it behaves when cutting

With 0.4% carbon, almost 2% chromium and some molybdenum, P20 behaves like a quenched and tempered 4140 that is one step harder. Chips are short and easy to control, but the cutting edge runs hotter than in a structural steel: flank wear shows up sooner and punishes weak edges. Because the block arrives pre-hardened and uniform, the goal is not maximum speed but a stable edge for the hours a cavity takes, since changing an insert halfway through a mould surface leaves a visible step.

Keys to machining it in the shop

Pre-hardened: machined at final hardness

P20 / 1.2311 is bought quenched and tempered (+QT), usually between 280 and 325 HB. That is the whole point of the grade: the cavity is machined at the hardness the mould will run at, and there is no later hardening to distort it. In exchange, check that hardness: in large blocks the core can be several points softer than the surface, and an insert cut from the middle of a block does not machine like a thin plate. Test with a hardness tester before programming and write the figure on the process sheet.

1.2311, 1.2312 or 1.2738: choosing the right block

1.2311 is the clean version of P20 and the one that polishes best, so it is chosen for mirror-finish or textured cavities. 1.2312 (40CrMnMoS8-6) has added sulphur: chips break better and it machines faster, but the sulphide inclusions prevent a good polish, so it is kept for mould plates and frames. 1.2738 adds nickel to keep hardness through very thick blocks. If the part will be polished, check the certificate says 1.2311 and not 1.2312.

Cavities: roughing, stress relief and finishing

Removing a lot of material releases the block's internal stresses, and the part can move a few tenths of a millimetre. For precision moulds, rough leaving 0.5-1 mm per side, stress relieve below the tempering temperature given by the supplier, then semi-finish and finish with even stock. For polishing, avoid sharp corners at the bottom of the cavity, leave radii the finishing cutter can follow and finish with light stepovers so the polisher starts from an even surface. If the mould will be nitrided for surface hardness, do it after finishing and pre-polishing.

Quick shop tips

  • Measure the real block hardness before programming: between 28 and 34 HRC the useful speed range changes.
  • For a mirror polish ask for 1.2311; 1.2312 machines better but will not polish well.
  • Rough cavities with a high-feed mill and leave even stock for finishing.
  • On precision parts, stress relieve between roughing and finishing: the block moves as you clear it.
  • With carbide in milling, air or dry is better than intermittent coolant: it avoids thermal cracks on the edge.

Frequently asked questions

Are 40CrMnMo7, 1.2311 and P20 the same steel?

In practice, yes: 40CrMnMo7 is the EN name, 1.2311 its material number and P20 the AISI designation of the equivalent mould steel. The compositions are very close and they machine the same; what really changes the result is the hardness the block arrives at.

What does +QT or +Q+T mean on 40CrMnMo7?

Quenched and tempered (pre-hardened), usually to 280-325 HB. It is the normal supply condition for moulds: it is machined directly and needs no heat treatment afterwards.

What is the difference between 1.2311 and 1.2312?

1.2312 has sulphur added to improve machinability: chips break better and you can run faster. In exchange, the sulphide inclusions prevent a good polish, so 1.2312 is used for plates and frames and 1.2311 for cavities that are polished or textured.

What cutting speed for P20 with an HSS drill?

Around a third of the carbide range (98-165 m/min): about 30-55 m/min (100-180 SFM). With a 10 mm HSS drill that is roughly 950-1,750 rpm, with plenty of coolant and pecks every two or three diameters.

Does P20 need hardening after machining?

No. It is supplied at its working hardness. What can be done is a stress relief after roughing on precision moulds and, if more surface hardness is wanted, nitriding at the end.

Similar materials

Related apps