M12 × 1.75
M12 thread pitch 1.75 mm and 10.2 mm tap drill size
ISO metric coarse thread · Ø 12 mm, pitch 1.75 mm · ISO 261 · ISO 68-1 · ISO 965
For your material and hole type
Generate the G84 / G76 / CYCLE84 cycle →Choose how to thread (tap, mill, lathe…) →M12 × 1.75 is the standard metric thread for 12 mm: if a drawing just says "M12", this is it. Here are its dimensions, tolerances, how to drill and tap it, the matching fasteners and how to repair it.
Thread dimensions
Designation
- Nominal diameter d
- 12 mm
- Pitch PCoarse pitch, single start: advances one pitch per turn
- 1.75 mm
- Profile angle
- 60°
- Tensile stress area AsUsed to calculate the bolt load
- 84.3 mm²
Basic diameters
- Pitch Ø d₂ = D₂
- 10.863 mm
- Screw minor Ø d₃
- 9.853 mm
- Nut minor Ø D₁
- 10.106 mm
- Fundamental triangle height H
- 1.516 mm
Basic values without tolerance: the actual manufacturing limits are in the next section.
- d
- Major Ø. Crest to crest; what calipers read.
- d₂
- Pitch Ø. Sets the fit; what gauges check.
- d₃
- Root Ø. Thinnest part of the screw.
- P
- Pitch. Advance per turn.
- H
- Theoretical height. Of the sharp-V profile.
Where it is used and its fine pitches
Machine bases, brackets, eye bolts, clamps and studs. There are three common pitches: 1.75 (coarse), 1.5 and 1.25 (fine, typical of automotive and hydraulics). An M12 socket head cap screw takes a 10 mm hex key and the nut an 18 mm wrench (19 mm in the old DIN 934).
Tolerances 6H / 6g
If the drawing gives no class, the medium class applies: 6H for the nut or tapped hole and 6g for the screw. These are the limits for M12 × 1.75.
| Part | Diameter | Minimum | Maximum |
|---|---|---|---|
| Screw 6g | Major Ø d | 11.701 | 11.966 |
| Screw 6g | Pitch Ø d₂ | 10.679 | 10.829 |
| Hole 6H | Pitch Ø D₂ | 10.863 | 11.063 |
| Hole 6H | Minor Ø D₁ | 10.106 | 10.441 |
The pitch diameter is checked with go / no-go gauges or the three-wire method; calipers only give the major diameter. Limits per ISO 965-2.
Drill and tap
Drills and feed
- Cutting-tap drillVÖLKEL · Metric cutting taps
- 10.2 mm
- Form-tap drillGuide value: confirm with the tap maker
- 11.1 mm
- Threading feedG95 F1.75 · in G94, F = RPM × pitch
- 1.75 mm/rev
Useful thread depth (guide)
| Steel | 1–1.5 × d | 12–18 mm |
| Cast iron | 1.5 × d | 18 mm |
| Aluminium and soft metals | 2 × d | 24 mm |
In a blind hole, drill deeper: useful thread + about 3 pitches for the tap lead and chips + the drill point. Steel example: 18 + 5.3 + 3.1 ≈ 27 mm.
10.2 mm drill. For a cutting tap, 10.2 mm. In tough materials or in production, use rigid tapping and coolant; on large parts or hard materials, thread milling avoids the risk of breaking a tap inside an expensive part.
Lathe threading: shim plate
Only if you single-point the thread on a lathe. The shim tilts the insert to follow the helix so it doesn't rub on one flank.
- Helix angleCalculated on the pitch diameter
- 2.94°
- Shim plateThe holder already has 1°; the shim adds +2°
- 3°
- External thread codeInsert size 16
- AE16+2
- Internal thread code
- AI16+2
For a right-hand thread with a right-hand holder. With a left-hand thread or the holder the other way round, the shim changes sign. Codes follow the usual threading-holder naming (AE external, AI internal): check your brand's catalogue.
Calculate the shim for your holder →M12 fasteners and assembly
What you need for the part that takes the screw: clearance hole, head recess, wrench sizes and tightening torque.
Clearance hole (ISO 273)
- Fine
- 13 mm
- MediumMost common
- 13.5 mm
- Coarse
- 14.5 mm
Head recess
- Counterbore for socket head cap screw (ISO 4762)DIN 974-1
- Ø20 × 13
- 90° countersink (DIN 7991)
- Ø24.4
Wrench sizes
- Hex head and nut (ISO 4017 / 4032)With DIN 933 / 934: 19 mm
- 18 mm
- Socket head cap screw (ISO 4762)
- 10 mm
- Countersunk socket screw (DIN 7991)
- 8 mm
Tightening torque (guide)
- Grade 8.8
- 80 N·m
- Grade 10.9
- 117 N·m
- Grade 12.9
- 137 N·m
Steel screw tightened to 90 % of yield with friction μ = 0.12 (no special lubrication). Oil, zinc plating or aluminium change it: the maker's table rules.
If the thread strips
- Helical insert (HeliCoil / Recoil)
- M12 × 1.75 STI
- STI tap drillAs supplied in insert kits
- 12.5 mm
- Usual insert length2 × d or more in aluminium
- 1.5 × d = 18 mm
With the insert the thread is M12 × 1.75 again: the original screw still fits. If the joint is taken apart often or carries high torque, a solid insert lasts longer; if changing the screw is fine, you can also go up one size.
Calculate the insert repair →How to tell it is M12 × 1.75
If you have the part or screw and don't know the thread, check the diameter first and then the pitch.
- 1. Measure the screw ODWith calipers on the crests. An M12 reads between 11.701 and 11.966 mm (a little less if worn).
- 2. Check the pitchA 1.75 mm pitch gauge should show no light between the teeth. Without a gauge: 5.7 threads in 10 mm.
- 3. If it's a tapped holeThe minor diameter is about 10.106–10.441 mm. Quickest check: try a known-good M12 screw.
Threads confused with M12 × 1.75
| Thread | Ø mm | Pitch mm | TPI | How to tell |
|---|---|---|---|---|
| M12 × 1.75 | 12 | 1.75 | 14.5 | This page |
| BSW 7/16"-14 | 11.113 | 1.814 | 14 | Nearly the same pitch (1.814 mm); Ø reads 11.11 mm; 55° profile |
| 7/16"-14 UNC | 11.113 | 1.814 | 14 | Nearly the same pitch (1.814 mm); Ø reads 11.11 mm |
| M12 × 1.5 | 12 | 1.5 | 16.9 | Same Ø, 1.5 mm pitch: the gauge won't seat |
| BSF 1/2"-16 | 12.7 | 1.588 | 16 | Nearly the same pitch (1.588 mm); Ø reads 12.7 mm; 55° profile |
| 1/2"-13 UNC | 12.7 | 1.954 | 13 | 12.7 mm Ø and 1.954 mm pitch |
Frequently asked questions
What drill is used for M12?+−
10.2 mm for a cutting tap. A form tap needs a larger hole (about 11.1 mm); confirm it with the tap’s data.
What is the pitch of M12?+−
The coarse pitch is 1.75 mm. The common fine pitches are 1.5 and 1.25 mm.
Are M12 and 1/2-13 UNC interchangeable?+−
No. 1/2-13 UNC is 12.7 mm with a 1.954 mm pitch. They look alike but do not thread into each other.