M4 × 0.7
M4 thread pitch 0.7 mm and 3.3 mm tap drill size
ISO metric coarse thread · Ø 4 mm, pitch 0.7 mm · ISO 261 · ISO 68-1 · ISO 965
For your material and hole type
Generate the G84 / G76 / CYCLE84 cycle →Choose how to thread (tap, mill, lathe…) →M4 × 0.7 is the standard metric thread for 4 mm: if a drawing just says "M4", this is it. Here are its dimensions, tolerances, how to drill and tap it, the matching fasteners and how to repair it.
Thread dimensions
Designation
- Nominal diameter d
- 4 mm
- Pitch PCoarse pitch, single start: advances one pitch per turn
- 0.7 mm
- Profile angle
- 60°
- Tensile stress area AsUsed to calculate the bolt load
- 8.8 mm²
Basic diameters
- Pitch Ø d₂ = D₂
- 3.545 mm
- Screw minor Ø d₃
- 3.141 mm
- Nut minor Ø D₁
- 3.242 mm
- Fundamental triangle height H
- 0.606 mm
Basic values without tolerance: the actual manufacturing limits are in the next section.
- d
- Major Ø. Crest to crest; what calipers read.
- d₂
- Pitch Ø. Sets the fit; what gauges check.
- d₃
- Root Ø. Thinnest part of the screw.
- P
- Pitch. Advance per turn.
- H
- Theoretical height. Of the sharp-V profile.
Where it is used and how to recognise it
Housings, small linear guides, covers, sensor brackets and moulds. An M4 socket head cap screw takes a 3 mm hex key and a standard M4 nut a 7 mm wrench. Measure the pitch with a thread gauge: 0.7 mm separates it from the M4 × 0.5 fine pitch.
Tolerances 6H / 6g
If the drawing gives no class, the medium class applies: 6H for the nut or tapped hole and 6g for the screw. These are the limits for M4 × 0.7.
| Part | Diameter | Minimum | Maximum |
|---|---|---|---|
| Screw 6g | Major Ø d | 3.838 | 3.978 |
| Screw 6g | Pitch Ø d₂ | 3.433 | 3.523 |
| Hole 6H | Pitch Ø D₂ | 3.545 | 3.663 |
| Hole 6H | Minor Ø D₁ | 3.242 | 3.422 |
The pitch diameter is checked with go / no-go gauges or the three-wire method; calipers only give the major diameter. Limits per ISO 965-2.
Drill and tap
Drills and feed
- Cutting-tap drillVÖLKEL · Metric cutting taps
- 3.3 mm
- Form-tap drillGuide value: confirm with the tap maker
- 3.6 mm
- Threading feedG95 F0.7 · in G94, F = RPM × pitch
- 0.7 mm/rev
Useful thread depth (guide)
| Steel | 1–1.5 × d | 4–6 mm |
| Cast iron | 1.5 × d | 6 mm |
| Aluminium and soft metals | 2 × d | 8 mm |
In a blind hole, drill deeper: useful thread + about 3 pitches for the tap lead and chips + the drill point. Steel example: 6 + 2.1 + 1 ≈ 10 mm.
3.3 mm drill. The cutting-tap drill is 3.3 mm. Do not use 3.2 or 3.5 mm “because that is what we have”: with 3.2 the tap is overloaded and breaks easily; with 3.5 the thread is too shallow and may strip when tightened. In blind holes, leave free depth below the useful thread.
Lathe threading: shim plate
Only if you single-point the thread on a lathe. The shim tilts the insert to follow the helix so it doesn't rub on one flank.
- Helix angleCalculated on the pitch diameter
- 3.6°
- Shim plateThe holder already has 1°; the shim adds +3°
- 4°
- External thread codeInsert size 11
- AE11+3
- Internal thread code
- AI11+3
For a right-hand thread with a right-hand holder. With a left-hand thread or the holder the other way round, the shim changes sign. Codes follow the usual threading-holder naming (AE external, AI internal): check your brand's catalogue.
Calculate the shim for your holder →M4 fasteners and assembly
What you need for the part that takes the screw: clearance hole, head recess, wrench sizes and tightening torque.
Clearance hole (ISO 273)
- Fine
- 4.3 mm
- MediumMost common
- 4.5 mm
- Coarse
- 4.8 mm
Head recess
- Counterbore for socket head cap screw (ISO 4762)DIN 974-1
- Ø8 × 4.4
- 90° countersink (DIN 7991)
- Ø9.4
Wrench sizes
- Hex head and nut (ISO 4017 / 4032)
- 7 mm
- Socket head cap screw (ISO 4762)
- 3 mm
- Countersunk socket screw (DIN 7991)
- 2.5 mm
Tightening torque (guide)
- Grade 8.8
- 2.8 N·m
- Grade 10.9
- 4.1 N·m
- Grade 12.9
- 4.8 N·m
Steel screw tightened to 90 % of yield with friction μ = 0.12 (no special lubrication). Oil, zinc plating or aluminium change it: the maker's table rules.
If the thread strips
- Helical insert (HeliCoil / Recoil)
- M4 × 0.7 STI
- STI tap drillAs supplied in insert kits
- 4.2 mm
- Usual insert length2 × d or more in aluminium
- 1.5 × d = 6 mm
With the insert the thread is M4 × 0.7 again: the original screw still fits. If the joint is taken apart often or carries high torque, a solid insert lasts longer; if changing the screw is fine, you can also go up one size.
Calculate the insert repair →How to tell it is M4 × 0.7
If you have the part or screw and don't know the thread, check the diameter first and then the pitch.
- 1. Measure the screw ODWith calipers on the crests. An M4 reads between 3.838 and 3.978 mm (a little less if worn).
- 2. Check the pitchA 0.7 mm pitch gauge should show no light between the teeth. Without a gauge: 14.3 threads in 10 mm.
- 3. If it's a tapped holeThe minor diameter is about 3.242–3.422 mm. Quickest check: try a known-good M4 screw.
Threads confused with M4 × 0.7
| Thread | Ø mm | Pitch mm | TPI | How to tell |
|---|---|---|---|---|
| M4 × 0.7 | 4 | 0.7 | 36.3 | This page |
| #8-36 UNF | 4.166 | 0.706 | 36 | Nearly the same pitch (0.706 mm); Ø reads 4.17 mm |
| 3 BA | 4.1 | 0.73 | 34.8 | Nearly the same pitch (0.73 mm); Ø reads 4.1 mm; 47.5° profile |
| 4 BA | 3.6 | 0.66 | 38.5 | Nearly the same pitch (0.66 mm); Ø reads 3.6 mm; 47.5° profile |
| #8-32 UNC | 4.166 | 0.794 | 32 | 4.17 mm Ø and 0.794 mm pitch |
| #6-40 UNF | 3.505 | 0.635 | 40 | Nearly the same pitch (0.635 mm); Ø reads 3.51 mm |
Frequently asked questions
What drill is used for M4?+−
3.3 mm for a cutting tap. A form tap needs a larger hole (about 3.6 mm); confirm it with the tap maker.
What is the pitch of M4?+−
The coarse pitch is 0.7 mm. The usual fine pitch is 0.5 mm.
Will an M4 thread take an #8-32 screw?+−
No. #8-32 UNC is 4.166 mm with a 0.794 mm pitch: the diameters are similar, but the pitch does not match and the thread gets damaged.