Skip to content

M20 × 2.5

M20 thread pitch 2.5 mm and 17.5 mm tap drill size

ISO metric coarse thread · Ø 20 mm, pitch 2.5 mm · ISO 261 · ISO 68-1 · ISO 965

M20 × 2.5 is the standard metric thread for 20 mm: if a drawing just says "M20", this is it. Here are its dimensions, tolerances, how to drill and tap it, the matching fasteners and how to repair it.

Thread dimensions

Designation

Nominal diameter d
20 mm
Pitch PCoarse pitch, single start: advances one pitch per turn
2.5 mm
Profile angle
60°
Tensile stress area AsUsed to calculate the bolt load
244.8 mm²

Basic diameters

Pitch Ø d₂ = D₂
18.376 mm
Screw minor Ø d₃
16.933 mm
Nut minor Ø D₁
17.294 mm
Fundamental triangle height H
2.165 mm

Basic values without tolerance: the actual manufacturing limits are in the next section.

d = 20d₂ = 18.376d₃ ≈ 16.933P = 2.560°Haxis
d
Major Ø. Crest to crest; what calipers read.
d₂
Pitch Ø. Sets the fit; what gauges check.
d₃
Root Ø. Thinnest part of the screw.
P
Pitch. Advance per turn.
H
Theoretical height. Of the sharp-V profile.
PartBasic profile
StandardISO 68-1
Height H2.165 mm
ScaleNTS · mm

Where it is used

Anchors, large eye bolts, machine bases, presses and heavy fixtures. An M20 socket head cap screw takes a 17 mm hex key and the nut a 30 mm wrench. The common fine pitches are 1.5 and 2 mm.

Tolerances 6H / 6g

If the drawing gives no class, the medium class applies: 6H for the nut or tapped hole and 6g for the screw. These are the limits for M20 × 2.5.

PartDiameterMinimumMaximum
Screw 6gMajor Ø d19.62319.958
Screw 6gPitch Ø d₂18.16418.334
Hole 6HPitch Ø D₂18.37618.600
Hole 6HMinor Ø D₁17.29417.744

The pitch diameter is checked with go / no-go gauges or the three-wire method; calipers only give the major diameter. Limits per ISO 965-2.

Drill and tap

Drills and feed

Cutting-tap drillVÖLKEL · Metric cutting taps
17.5 mm
Form-tap drillGuide value: confirm with the tap maker
19 mm
Threading feedG95 F2.5 · in G94, F = RPM × pitch
2.5 mm/rev

Useful thread depth (guide)

Steel1–1.5 × d20–30 mm
Cast iron1.5 × d30 mm
Aluminium and soft metals2 × d40 mm

In a blind hole, drill deeper: useful thread + about 3 pitches for the tap lead and chips + the drill point. Steel example: 30 + 7.5 + 5.3 ≈ 43 mm.

17.5 mm drill and how to machine it. For a cutting tap, 17.5 mm. An M20 tap needs a lot of torque: on a small mill or a weak taper it is safer to thread mill. On a lathe, an M20 internal thread is cut with a threading bar or a tap in the tailstock, depending on the batch.

Lathe threading: shim plate

Only if you single-point the thread on a lathe. The shim tilts the insert to follow the helix so it doesn't rub on one flank.

Helix angleCalculated on the pitch diameter
2.48°
Shim plateThe holder already has 1°; the shim adds +1°
2°
External thread codeInsert size 16
AE16+1
Internal thread code
AI16+1

For a right-hand thread with a right-hand holder. With a left-hand thread or the holder the other way round, the shim changes sign. Codes follow the usual threading-holder naming (AE external, AI internal): check your brand's catalogue.

Calculate the shim for your holder →

M20 fasteners and assembly

What you need for the part that takes the screw: clearance hole, head recess, wrench sizes and tightening torque.

Clearance hole (ISO 273)

Fine
21 mm
MediumMost common
22 mm
Coarse
24 mm

Wrench sizes

Hex head and nut (ISO 4017 / 4032)
30 mm
Socket head cap screw (ISO 4762)
17 mm

Tightening torque (guide)

Grade 8.8
392 N·m
Grade 10.9
558 N·m
Grade 12.9
653 N·m

Steel screw tightened to 90 % of yield with friction μ = 0.12 (no special lubrication). Oil, zinc plating or aluminium change it: the maker's table rules.

If the thread strips

Helical insert (HeliCoil / Recoil)
M20 × 2.5 STI
STI tap drillAs supplied in insert kits
20.75 mm
Usual insert length2 × d or more in aluminium
1.5 × d = 30 mm

With the insert the thread is M20 × 2.5 again: the original screw still fits. If the joint is taken apart often or carries high torque, a solid insert lasts longer; if changing the screw is fine, you can also go up one size.

Calculate the insert repair →

How to tell it is M20 × 2.5

If you have the part or screw and don't know the thread, check the diameter first and then the pitch.

  1. 1. Measure the screw ODWith calipers on the crests. An M20 reads between 19.623 and 19.958 mm (a little less if worn).
  2. 2. Check the pitchA 2.5 mm pitch gauge should show no light between the teeth. Without a gauge: 4 threads in 10 mm.
  3. 3. If it's a tapped holeThe minor diameter is about 17.294–17.744 mm. Quickest check: try a known-good M20 screw.

Threads confused with M20 × 2.5

ThreadØ mmPitch mmTPIHow to tell
M20 × 2.5202.510.2This page
BSW 3/4"-1019.052.5410Nearly the same pitch (2.54 mm); Ø reads 19.05 mm; 55° profile
3/4"-10 UNC19.052.5410Nearly the same pitch (2.54 mm); Ø reads 19.05 mm
M20 × 220212.7Same Ø, 2 mm pitch: the gauge won't seat
BSF 3/4"-1219.052.1171219.05 mm Ø and 2.117 mm pitch; 55° profile
G 1/2-14 BSP20.9551.8141420.96 mm Ø and 1.814 mm pitch; 55° profile
Identify a thread from your measurements →

Frequently asked questions

What drill is used for M20?+

17.5 mm for a cutting tap. A form tap needs a larger hole (about 19 mm); confirm it with the tap maker.

What is the pitch of M20?+

The coarse pitch is 2.5 mm. The common fine pitches are 1.5 and 2 mm.

Are M20 and 3/4-10 UNC the same?+

No. 3/4-10 UNC is 19.05 mm with a 2.54 mm pitch: they are not interchangeable.

Sources: profile and diameters, ISO 68-1 and ISO 261; tolerances, ISO 965-2; drill, VÖLKEL · Metric cutting taps; clearance hole, ISO 273; counterbore, DIN 974-1; wrench sizes, ISO 4017, ISO 4032, ISO 4762 and DIN 7991; tightening torque, Technical information: screws and nuts (μ = 0.12). Reference data: the drawing, tolerance class and maker's instructions govern. A cutting-tap drill is not for form tapping. Reviewed on .