M5 × 0.8
M5 thread pitch 0.8 mm and 4.2 mm tap drill size
ISO metric coarse thread · Ø 5 mm, pitch 0.8 mm · ISO 261 · ISO 68-1 · ISO 965
For your material and hole type
Generate the G84 / G76 / CYCLE84 cycle →Choose how to thread (tap, mill, lathe…) →M5 × 0.8 is the standard metric thread for 5 mm: if a drawing just says "M5", this is it. Here are its dimensions, tolerances, how to drill and tap it, the matching fasteners and how to repair it.
Thread dimensions
Designation
- Nominal diameter d
- 5 mm
- Pitch PCoarse pitch, single start: advances one pitch per turn
- 0.8 mm
- Profile angle
- 60°
- Tensile stress area AsUsed to calculate the bolt load
- 14.2 mm²
Basic diameters
- Pitch Ø d₂ = D₂
- 4.48 mm
- Screw minor Ø d₃
- 4.019 mm
- Nut minor Ø D₁
- 4.134 mm
- Fundamental triangle height H
- 0.693 mm
Basic values without tolerance: the actual manufacturing limits are in the next section.
- d
- Major Ø. Crest to crest; what calipers read.
- d₂
- Pitch Ø. Sets the fit; what gauges check.
- d₃
- Root Ø. Thinnest part of the screw.
- P
- Pitch. Advance per turn.
- H
- Theoretical height. Of the sharp-V profile.
Where it is used
M5 pneumatic fittings, aluminium extrusion with T-nuts, brackets, covers and fixtures. An M5 socket head cap screw takes a 4 mm hex key and an M5 nut an 8 mm wrench. On machines of American origin, a “5 mm” hole may really be #10-24 or #10-32: measure the pitch before tapping or fitting a screw.
Tolerances 6H / 6g
If the drawing gives no class, the medium class applies: 6H for the nut or tapped hole and 6g for the screw. These are the limits for M5 × 0.8.
| Part | Diameter | Minimum | Maximum |
|---|---|---|---|
| Screw 6g | Major Ø d | 4.826 | 4.976 |
| Screw 6g | Pitch Ø d₂ | 4.361 | 4.456 |
| Hole 6H | Pitch Ø D₂ | 4.480 | 4.605 |
| Hole 6H | Minor Ø D₁ | 4.134 | 4.334 |
The pitch diameter is checked with go / no-go gauges or the three-wire method; calipers only give the major diameter. Limits per ISO 965-2.
Drill and tap
Drills and feed
- Cutting-tap drillVÖLKEL · Metric cutting taps
- 4.2 mm
- Form-tap drillGuide value: confirm with the tap maker
- 4.6 mm
- Threading feedG95 F0.8 · in G94, F = RPM × pitch
- 0.8 mm/rev
Useful thread depth (guide)
| Steel | 1–1.5 × d | 5–7.5 mm |
| Cast iron | 1.5 × d | 7.5 mm |
| Aluminium and soft metals | 2 × d | 10 mm |
In a blind hole, drill deeper: useful thread + about 3 pitches for the tap lead and chips + the drill point. Steel example: 7.5 + 2.4 + 1.3 ≈ 12 mm.
4.2 mm drill. The cutting-tap drill is 4.2 mm. In soft aluminium, tapping with the correct drill and a sharp tap gives a better thread than opening up the hole. In blind holes, calculate the drilled depth separately from the useful thread: the tap’s chamfer does not cut a full thread in its first turns.
Lathe threading: shim plate
Only if you single-point the thread on a lathe. The shim tilts the insert to follow the helix so it doesn't rub on one flank.
- Helix angleCalculated on the pitch diameter
- 3.25°
- Shim plateThe holder already has 1°; the shim adds +2°
- 3°
- External thread codeInsert size 11
- AE11+2
- Internal thread code
- AI11+2
For a right-hand thread with a right-hand holder. With a left-hand thread or the holder the other way round, the shim changes sign. Codes follow the usual threading-holder naming (AE external, AI internal): check your brand's catalogue.
Calculate the shim for your holder →M5 fasteners and assembly
What you need for the part that takes the screw: clearance hole, head recess, wrench sizes and tightening torque.
Clearance hole (ISO 273)
- Fine
- 5.3 mm
- MediumMost common
- 5.5 mm
- Coarse
- 5.8 mm
Head recess
- Counterbore for socket head cap screw (ISO 4762)DIN 974-1
- Ø10 × 5.4
- 90° countersink (DIN 7991)
- Ø10.4
Wrench sizes
- Hex head and nut (ISO 4017 / 4032)
- 8 mm
- Socket head cap screw (ISO 4762)
- 4 mm
- Countersunk socket screw (DIN 7991)
- 3 mm
Tightening torque (guide)
- Grade 8.8
- 5.5 N·m
- Grade 10.9
- 8.1 N·m
- Grade 12.9
- 9.5 N·m
Steel screw tightened to 90 % of yield with friction μ = 0.12 (no special lubrication). Oil, zinc plating or aluminium change it: the maker's table rules.
If the thread strips
- Helical insert (HeliCoil / Recoil)
- M5 × 0.8 STI
- STI tap drillAs supplied in insert kits
- 5.2 mm
- Usual insert length2 × d or more in aluminium
- 1.5 × d = 7.5 mm
With the insert the thread is M5 × 0.8 again: the original screw still fits. If the joint is taken apart often or carries high torque, a solid insert lasts longer; if changing the screw is fine, you can also go up one size.
Calculate the insert repair →How to tell it is M5 × 0.8
If you have the part or screw and don't know the thread, check the diameter first and then the pitch.
- 1. Measure the screw ODWith calipers on the crests. An M5 reads between 4.826 and 4.976 mm (a little less if worn).
- 2. Check the pitchA 0.8 mm pitch gauge should show no light between the teeth. Without a gauge: 12.5 threads in 10 mm.
- 3. If it's a tapped holeThe minor diameter is about 4.134–4.334 mm. Quickest check: try a known-good M5 screw.
Threads confused with M5 × 0.8
| Thread | Ø mm | Pitch mm | TPI | How to tell |
|---|---|---|---|---|
| M5 × 0.8 | 5 | 0.8 | 31.8 | This page |
| #10-32 UNF | 4.826 | 0.794 | 32 | Nearly the same pitch (0.794 mm); Ø reads 4.83 mm |
| BSF 3/16"-32 | 4.763 | 0.794 | 32 | Nearly the same pitch (0.794 mm); Ø reads 4.76 mm; 55° profile |
| 2 BA | 4.7 | 0.81 | 31.4 | Nearly the same pitch (0.81 mm); Ø reads 4.7 mm; 47.5° profile |
| #12-32 UNEF | 5.486 | 0.794 | 32 | Nearly the same pitch (0.794 mm); Ø reads 5.49 mm |
| 1 BA | 5.3 | 0.9 | 28.2 | 5.3 mm Ø and 0.9 mm pitch; 47.5° profile |
Frequently asked questions
What drill is used for M5?+−
4.2 mm for a cutting tap. A form tap needs a larger hole (about 4.6 mm); confirm it with the tap’s data.
What is the pitch of M5?+−
The coarse pitch is 0.8 mm. M5 × 0.5 fine pitch also exists.
Is M5 the same as #10-24 or #10-32?+−
No. #10 threads are 4.826 mm with 24 or 32 threads per inch (1.058 or 0.794 mm pitch). They are not interchangeable with M5.