M16 × 2
M16 thread pitch 2 mm and 14 mm tap drill size
ISO metric coarse thread · Ø 16 mm, pitch 2 mm · ISO 261 · ISO 68-1 · ISO 965
For your material and hole type
Generate the G84 / G76 / CYCLE84 cycle →Choose how to thread (tap, mill, lathe…) →M16 × 2 is the standard metric thread for 16 mm: if a drawing just says "M16", this is it. Here are its dimensions, tolerances, how to drill and tap it, the matching fasteners and how to repair it.
Thread dimensions
Designation
- Nominal diameter d
- 16 mm
- Pitch PCoarse pitch, single start: advances one pitch per turn
- 2 mm
- Profile angle
- 60°
- Tensile stress area AsUsed to calculate the bolt load
- 156.7 mm²
Basic diameters
- Pitch Ø d₂ = D₂
- 14.701 mm
- Screw minor Ø d₃
- 13.546 mm
- Nut minor Ø D₁
- 13.835 mm
- Fundamental triangle height H
- 1.732 mm
Basic values without tolerance: the actual manufacturing limits are in the next section.
- d
- Major Ø. Crest to crest; what calipers read.
- d₂
- Pitch Ø. Sets the fit; what gauges check.
- d₃
- Root Ø. Thinnest part of the screw.
- P
- Pitch. Advance per turn.
- H
- Theoretical height. Of the sharp-V profile.
Where it is used
Frames, anchors, lifting eye bolts, flanges and machine bases. An M16 socket head cap screw takes a 14 mm hex key and the nut a 24 mm wrench. The usual fine pitch is M16 × 1.5, common in hydraulics and lock nuts.
Tolerances 6H / 6g
If the drawing gives no class, the medium class applies: 6H for the nut or tapped hole and 6g for the screw. These are the limits for M16 × 2.
| Part | Diameter | Minimum | Maximum |
|---|---|---|---|
| Screw 6g | Major Ø d | 15.682 | 15.962 |
| Screw 6g | Pitch Ø d₂ | 14.503 | 14.663 |
| Hole 6H | Pitch Ø D₂ | 14.701 | 14.913 |
| Hole 6H | Minor Ø D₁ | 13.835 | 14.210 |
The pitch diameter is checked with go / no-go gauges or the three-wire method; calipers only give the major diameter. Limits per ISO 965-2.
Drill and tap
Drills and feed
- Cutting-tap drillVÖLKEL · Metric cutting taps
- 14 mm
- Form-tap drillGuide value: confirm with the tap maker
- 15 mm
- Threading feedG95 F2 · in G94, F = RPM × pitch
- 2 mm/rev
Useful thread depth (guide)
| Steel | 1–1.5 × d | 16–24 mm |
| Cast iron | 1.5 × d | 24 mm |
| Aluminium and soft metals | 2 × d | 32 mm |
In a blind hole, drill deeper: useful thread + about 3 pitches for the tap lead and chips + the drill point. Steel example: 24 + 6 + 4.2 ≈ 35 mm.
14 mm drill and tapping torque. For a cutting tap, 14 mm. An M16 tap takes a lot of torque: on a machining centre use rigid tapping with plenty of coolant and check that the spindle and taper can take it. On expensive parts or hard materials, thread milling is safer and lets you adjust size with the offset.
Lathe threading: shim plate
Only if you single-point the thread on a lathe. The shim tilts the insert to follow the helix so it doesn't rub on one flank.
- Helix angleCalculated on the pitch diameter
- 2.48°
- Shim plateThe holder already has 1°; the shim adds +1°
- 2°
- External thread codeInsert size 16
- AE16+1
- Internal thread code
- AI16+1
For a right-hand thread with a right-hand holder. With a left-hand thread or the holder the other way round, the shim changes sign. Codes follow the usual threading-holder naming (AE external, AI internal): check your brand's catalogue.
Calculate the shim for your holder →M16 fasteners and assembly
What you need for the part that takes the screw: clearance hole, head recess, wrench sizes and tightening torque.
Clearance hole (ISO 273)
- Fine
- 17 mm
- MediumMost common
- 17.5 mm
- Coarse
- 18.5 mm
Head recess
- Counterbore for socket head cap screw (ISO 4762)DIN 974-1
- Ø26 × 17.5
- 90° countersink (DIN 7991)
- Ø32.4
Wrench sizes
- Hex head and nut (ISO 4017 / 4032)
- 24 mm
- Socket head cap screw (ISO 4762)
- 14 mm
- Countersunk socket screw (DIN 7991)
- 10 mm
Tightening torque (guide)
- Grade 8.8
- 194 N·m
- Grade 10.9
- 285 N·m
- Grade 12.9
- 333 N·m
Steel screw tightened to 90 % of yield with friction μ = 0.12 (no special lubrication). Oil, zinc plating or aluminium change it: the maker's table rules.
If the thread strips
- Helical insert (HeliCoil / Recoil)
- M16 × 2 STI
- STI tap drillAs supplied in insert kits
- 16.5 mm
- Usual insert length2 × d or more in aluminium
- 1.5 × d = 24 mm
With the insert the thread is M16 × 2 again: the original screw still fits. If the joint is taken apart often or carries high torque, a solid insert lasts longer; if changing the screw is fine, you can also go up one size.
Calculate the insert repair →How to tell it is M16 × 2
If you have the part or screw and don't know the thread, check the diameter first and then the pitch.
- 1. Measure the screw ODWith calipers on the crests. An M16 reads between 15.682 and 15.962 mm (a little less if worn).
- 2. Check the pitchA 2 mm pitch gauge should show no light between the teeth. Without a gauge: 5 threads in 10 mm.
- 3. If it's a tapped holeThe minor diameter is about 13.835–14.21 mm. Quickest check: try a known-good M16 screw.
Threads confused with M16 × 2
| Thread | Ø mm | Pitch mm | TPI | How to tell |
|---|---|---|---|---|
| M16 × 2 | 16 | 2 | 12.7 | This page |
| BSF 5/8"-14 | 15.875 | 1.814 | 14 | Nearly the same pitch (1.814 mm); Ø reads 15.88 mm; 55° profile |
| BSW 5/8"-11 | 15.875 | 2.309 | 11 | 15.88 mm Ø and 2.309 mm pitch; 55° profile |
| 5/8"-11 UNC | 15.875 | 2.309 | 11 | 15.88 mm Ø and 2.309 mm pitch |
| M16 × 1.5 | 16 | 1.5 | 16.9 | Same Ø, 1.5 mm pitch: the gauge won't seat |
| 5/8"-18 UNF | 15.875 | 1.411 | 18 | 15.88 mm Ø and 1.411 mm pitch |
Frequently asked questions
What drill is used for M16?+−
14 mm for a cutting tap. A form tap needs a larger hole (about 15 mm); confirm it with the tap maker.
What is the pitch of M16?+−
The coarse pitch is 2 mm. The most used fine pitch is 1.5 mm.
Is it better to tap or thread mill M16?+−
In production and ordinary steel, tapping is faster. On expensive parts, hard materials or when size must be adjusted, thread milling is safer.