M3 × 0.5
M3 thread pitch 0.5 mm and 2.5 mm tap drill size
ISO metric coarse thread · Ø 3 mm, pitch 0.5 mm · ISO 261 · ISO 68-1 · ISO 965
For your material and hole type
Generate the G84 / G76 / CYCLE84 cycle →Choose how to thread (tap, mill, lathe…) →M3 × 0.5 is the standard metric thread for 3 mm: if a drawing just says "M3", this is it. Here are its dimensions, tolerances, how to drill and tap it, the matching fasteners and how to repair it.
Thread dimensions
Designation
- Nominal diameter d
- 3 mm
- Pitch PCoarse pitch, single start: advances one pitch per turn
- 0.5 mm
- Profile angle
- 60°
- Tensile stress area AsUsed to calculate the bolt load
- 5 mm²
Basic diameters
- Pitch Ø d₂ = D₂
- 2.675 mm
- Screw minor Ø d₃
- 2.387 mm
- Nut minor Ø D₁
- 2.459 mm
- Fundamental triangle height H
- 0.433 mm
Basic values without tolerance: the actual manufacturing limits are in the next section.
- d
- Major Ø. Crest to crest; what calipers read.
- d₂
- Pitch Ø. Sets the fit; what gauges check.
- d₃
- Root Ø. Thinnest part of the screw.
- P
- Pitch. Advance per turn.
- H
- Theoretical height. Of the sharp-V profile.
Where it is used
Small electronics hardware, sheet-metal covers, sensors, light fixtures and circuit boards. An M3 socket head cap screw (ISO 4762) takes a 2.5 mm hex key and a standard M3 nut a 5.5 mm wrench: useful hints, but no substitute for measuring the pitch.
Tolerances 6H / 6g
If the drawing gives no class, the medium class applies: 6H for the nut or tapped hole and 6g for the screw. These are the limits for M3 × 0.5.
| Part | Diameter | Minimum | Maximum |
|---|---|---|---|
| Screw 6g | Major Ø d | 2.874 | 2.980 |
| Screw 6g | Pitch Ø d₂ | 2.580 | 2.655 |
| Hole 6H | Pitch Ø D₂ | 2.675 | 2.775 |
| Hole 6H | Minor Ø D₁ | 2.459 | 2.599 |
The pitch diameter is checked with go / no-go gauges or the three-wire method; calipers only give the major diameter. Limits per ISO 965-2.
Drill and tap
Drills and feed
- Cutting-tap drillVÖLKEL · Metric cutting taps
- 2.5 mm
- Form-tap drillGuide value: confirm with the tap maker
- 2.75 mm
- Threading feedG95 F0.5 · in G94, F = RPM × pitch
- 0.5 mm/rev
Useful thread depth (guide)
| Steel | 1–1.5 × d | 3–4.5 mm |
| Cast iron | 1.5 × d | 4.5 mm |
| Aluminium and soft metals | 2 × d | 6 mm |
In a blind hole, drill deeper: useful thread + about 3 pitches for the tap lead and chips + the drill point. Steel example: 4.5 + 1.5 + 0.8 ≈ 7 mm.
2.5 mm drill and how not to break the tap. With a cutting tap, drill 2.5 mm. In blind holes leave extra depth below the useful thread and use a spiral-flute tap to lift the chips; in through holes, a spiral-point tap. Lubricate well and, on a machine, use rigid tapping or a holder with a clutch: an M3 tap snaps before you feel the load.
Lathe threading: shim plate
Only if you single-point the thread on a lathe. The shim tilts the insert to follow the helix so it doesn't rub on one flank.
- Helix angleCalculated on the pitch diameter
- 3.4°
- Shim plateThe holder already has 1°; the shim adds +2°
- 3°
- External thread codeInsert size 11
- AE11+2
- Internal thread code
- AI11+2
For a right-hand thread with a right-hand holder. With a left-hand thread or the holder the other way round, the shim changes sign. Codes follow the usual threading-holder naming (AE external, AI internal): check your brand's catalogue.
Calculate the shim for your holder →M3 fasteners and assembly
What you need for the part that takes the screw: clearance hole, head recess, wrench sizes and tightening torque.
Clearance hole (ISO 273)
- Fine
- 3.2 mm
- MediumMost common
- 3.4 mm
- Coarse
- 3.6 mm
Head recess
- Counterbore for socket head cap screw (ISO 4762)DIN 974-1
- Ø6.5 × 3.3
- 90° countersink (DIN 7991)
- Ø6.3
Wrench sizes
- Hex head and nut (ISO 4017 / 4032)
- 5.5 mm
- Socket head cap screw (ISO 4762)
- 2.5 mm
- Countersunk socket screw (DIN 7991)
- 2 mm
If the thread strips
- Helical insert (HeliCoil / Recoil)
- M3 × 0.5 STI
- STI tap drillAs supplied in insert kits
- 3.2 mm
- Usual insert length2 × d or more in aluminium
- 1.5 × d = 4.5 mm
With the insert the thread is M3 × 0.5 again: the original screw still fits. If the joint is taken apart often or carries high torque, a solid insert lasts longer; if changing the screw is fine, you can also go up one size.
Calculate the insert repair →How to tell it is M3 × 0.5
If you have the part or screw and don't know the thread, check the diameter first and then the pitch.
- 1. Measure the screw ODWith calipers on the crests. An M3 reads between 2.874 and 2.98 mm (a little less if worn).
- 2. Check the pitchA 0.5 mm pitch gauge should show no light between the teeth. Without a gauge: 20 threads in 10 mm.
- 3. If it's a tapped holeThe minor diameter is about 2.459–2.599 mm. Quickest check: try a known-good M3 screw.
Threads confused with M3 × 0.5
| Thread | Ø mm | Pitch mm | TPI | How to tell |
|---|---|---|---|---|
| M3 × 0.5 | 3 | 0.5 | 50.8 | This page |
| #4-48 UNF | 2.845 | 0.529 | 48 | Nearly the same pitch (0.529 mm); Ø reads 2.85 mm |
| 6 BA | 2.8 | 0.53 | 47.9 | Nearly the same pitch (0.53 mm); Ø reads 2.8 mm; 47.5° profile |
| 7 BA | 2.5 | 0.48 | 52.9 | Nearly the same pitch (0.48 mm); Ø reads 2.5 mm; 47.5° profile |
| #5-44 UNF | 3.175 | 0.577 | 44 | 3.18 mm Ø and 0.577 mm pitch |
| #3-48 UNC | 2.515 | 0.529 | 48 | Nearly the same pitch (0.529 mm); Ø reads 2.52 mm |
Frequently asked questions
What drill is used for M3?+−
2.5 mm for a cutting tap. A form tap needs a larger hole (about 2.75 mm): confirm it with the tap’s data.
What is the pitch of an M3 thread?+−
The coarse pitch of M3 is 0.5 mm. There is also M3 × 0.35 fine pitch, which is much less common.
Are M3 and #4-40 UNC interchangeable?+−
No. #4-40 is 2.845 mm with a 0.635 mm pitch: the screw may start a few turns, but it binds and damages the thread.